update of similar parts.

  • Thread starter Thread starter samurai
  • Start date Start date
S

samurai

SW2006

I've got a driveshaft, PartA, that is in production and fully
dimensioned.
Now I want to make PartB with some drastic changes to one end of the
drive shaft, but keep everything else the same on the opposite end of
the driveshaft. And this may also result in another PartC.

What is the best way to make a change in Part A, so it will also
update parts B,and C? For ex, a small diameter change of Part A, so
the same diameter will change in parts B, C and D?

Do I have to use an Equation to link to part A? Is there anything
else that can be done? Should I also save a copy of Part A to Part B,
and C then add/make changes to B and C. I dont' think I can use a
spreadsheet/design table, b/c parts B and C have some drastic changes
on the one end of the driveshaft.

Also, I would then like to use the drawing from partA with all the
dimensions, and be able to dimension most of part B and C. How can i
do this?

Right now, i just saved partA as PartB and PartC, and now manually
make changes to A, B and C as they are needed, but is a pain in the
butt, if I make a change in A, it does not update B and C in the part
and drawing. Also, I really do not want to re-dimension a drawing for
part B and C, when A has most of everything.

How can I be a little more efficient at this?

samurai.
 
Use configurations of part A. Part B exists as a configuration in part
A.sldprt. Drawing B is a copy of drawing A. Edit the properties of each
drawing view to reference configuration B. The common dimensions will
remain, and others will dangle. Do the same for Part C and any other part
that will always be a derivation part A.
 
You can copy the drawings as well as the parts using "Save as", then
the common drawing dimensions will carry over.

Don't be lazy. Keep the parts separate. Don't get too clever with
configurations or links, even though doing so will make you feel like
a SW god. In the long run, separate parts changed separately will be
easier to manage.

My current client is paying me good money to undo the headaches caused
by a previous user's excessive "configuration cleverness". That's on
top of the money lost to bad parts and service calls.
 
i feel u can use design table also

and supress of the changes or the feature which are not required in
either of the part.

make only one dwg

then make copy of it and link it with the other configurations

Regards

Deepak
 
Use configurations of part A. Part B exists as a configuration in part
A.sldprt. Drawing B is a copy of drawing A. Edit the properties of each
drawing view to reference configuration B. The common dimensions will
remain, and others will dangle. Do the same for Part C and any other part
that will always be a derivation part A.
Click to expand...

This works for me, but now how do I generate a drawing of partB from
partA, dimensioning only the new configurations and dimensions of
partB, with the rest of the dimensions coming from partA?

samurai.
 
The drawing for each new configuration would be a copy of the drawing of
part A. In each copy, point each drawing view to the new configuration.
Existing dimensions and annotations will remain, and dimensions to missing
geometry will go dangling (and may be hidden automatically).
 
If you insert A as a part in a new part B, then you can remove the
features from A in B that you don't like and add the new features to B
without danger of affecting A. You can then make a drawing of B
without the dimensions from A coming in.

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