Origin (move), -or- "did" the pooch on this one...

Discussion in 'SolidWorks' started by Mike Tripoli, May 19, 2004.

  1. Mike Tripoli

    Mike Tripoli Guest

    Hello,

    OK, this is going to be boring. Also, you will ask yourself
    "why did he do that"?

    I imported an STL as a solid body (it's a diamond gemstone). I
    only needed the crown and facets.

    Using the imported solid body, I assigned reference planes to
    each facet (on their respective surface). Insert a sketch, select the
    facet face, convert entities and got my new sketch. Extruded this to
    1mm thick (for those interested, I did it "reversed" so that each
    facet would merge into the next. OK, got the entire crown. Now...

    When I delete the "original"solid body, I loose the reference
    for all the planes (as they were converted entities), so now I have an
    entire assembly tree with exclamation points, and no reference
    "origin" for the model. I can keep working with this, as all the other
    features are relative to the solid, but it's bugging the hell out of
    me having all these exclamation points. How can I move the model (or
    origin) let's say to the center of the "top flat" face, and get rid of
    all the exclamations?

    Thank you for your help, and yes, I've already called myself
    all the "dumb f*** names...

    MT
     
    Mike Tripoli, May 19, 2004
    #1
  2. If you exported it out as a dumb part and bring it back in as you did, then
    the link to the original will be lost along with the exclamations. I would
    have hidden, suppressed or made transparent the original if you didn't want
    to see it.

    Keith
     
    Keith Streich, May 19, 2004
    #2
  3. Yes, that will happen, you deleted all you references so... one way to
    get rid of the exclamation points is to export the body as a parasolid
    x_t and reimport it (and of course delete all the ref planes).
    As for your origin.. well, you could also predefine a coordinate system
    and when you export the parasolid, you again use the options tab to
    select the coordinate system (origin).

    I can imagine how you are going about this but I'd suggest (although I'm
    sure it works) that you not approach each facet as a solid extrusion,..
    use a planar surface and after you have all your faces (btw, if the data
    is symmetrical, you could establish a centerline and copy/rotate the
    faces), then knit the surfaces into a solid.

    BTW, here is a solid model of a diamond I did many years ago..
    http://www.zxys.com/swparts/zircrung.zip

    ...
     
    Paul Salvador, May 19, 2004
    #3
  4. Mike Tripoli

    Mike Tripoli Guest

    Hi Paul,

    Thanks for the info and the example part. I examined your
    design, and re-created what I was working on using the same
    techniques. Much better result! Thank you again.

    Mike T.
     
    Mike Tripoli, May 21, 2004
    #4
Ask a Question

Want to reply to this thread or ask your own question?

You'll need to choose a username for the site, which only take a couple of moments (here). After that, you can post your question and our members will help you out.