drawing in wildfire

When creating drawings from parts, dimensions display with upper and lower
limits. Does anyone now how to make the default setting 'nominal'.
Thanks
Andrea

 

tol_display YES - in your drawing .dtl file

tol_mode nominal - in config,pro

Models created before this config setting is changed will not show as
nominal as default - therefore if you create a drawing from an older model
and change the .dtl to tol_display YES then all the dims will change to
limits not nominal - you would then have to select all the dims to change
them to nominal - possible on 2000i2 but not 2001 - I haven't checked on
Wildfire yet but this mapkey will work on 2001 and Wildfire to 'box' select
dims

mapkey $F7 @MAPKEY_NAME Drag Window To Modify Dimensions;\
mapkey(continued) @MAPKEY_LABELModify_Dimensions_Many;#MODIFY;#DIMENSION;
#PICK MANY

- I think you can put #PICK ALL in there as an alternative

Sean

--
~~~~~~~~~~~~~~~~~~~~~~~~~~~~

Sean Kerslake
Dept. Design & Technology
Loughborough University
LE11 3TU
UK



01509 228317

 

config.pro:

tol_mode nominal

Rui

 

Hi Andrea

"In config.pro set tol_display to no for no tolerances to be displayed at all
or set to yes and tol_display to nominal if at some point you may wish to
display tolerances in your drawings."

I had the same problem, the above was obtained through this group.

Geoff